> For the complete documentation index, see [llms.txt](https://dante-solutions-inc.gitbook.io/dante-6.3-help-documentation/llms.txt). Markdown versions of documentation pages are available by appending `.md` to page URLs; this page is available as [Markdown](https://dante-solutions-inc.gitbook.io/dante-6.3-help-documentation/introduction/create-stress-model-input-file-by-editing-thermal-model-input-file.md).
# Create Stress Model Input File by Editing Thermal Model Input File
## Change the heading name (optional)
```
*Heading
** Job name: Cylinder_2D_s Model name: Cylinder_2D_s
```
## Change the element type from thermal element to stress element
```
*Element, type=DCAX4
```
* to
```
*Element, type=CAX4
```
## In the ***\*Step*** definition for all the steps, change ***\*Heat Transfer*** to ***\*Static***
## Fix one node for the stress analysis
***Inside Assembly***
```
*Nset, nset=Fixed_Y_Node, instance=cylinder-2d-1
16,
```
**After Assembly, and before \*Step**
```
*BOUNDARY
Fixed_Y_Node, 2, 2
```
## Change the ***User Material type***
from ***Thermal*** to ***Mechanical,*** and change the second material constant from -3 to -4.
```
*User Material, constants=24, type=THERMAL
** Row1 (1rd:Density),(2nd:ModelType),(3rd-8th:F,P,UB,LB,M,TM)
7.83e-06, -3., 0.3, 0.7, 0., 0., 0., 0.
** Note: with "-1.", the default alloy value from the material database will be used
** The default value is available in material *DQT file or the Powepoint pdf file
** Row-2: GS:1, Mn:3, Si:4, Ni:5, Cr:6, Mo:7, Cu:8, V:9
0.0635, 0.6, 0.3, 0.1, 0.1, 0.05, -1., -1.
** Row-3: P:10, Nb:11, Al:12, Ti:13, W:14, Co:15, B:16, N:17
-1., -1., 0., 0., -1., -1., 0., -1.
```
to
```
*User Material, constants=24, type=MECHNICAL
7.83e-06, -4., 0.3, 0.7, 0., 0., 0., 0.
0.0635, 0.6, 0.3, 0.1, 0.1, 0.05, -1., -1.
-1., -1., 0., 0., -1., -1., 0., -1.
```
## Define ***\*Controls*** card in the first step.
```
*CONTROLS, PARAMETERS=LINE SEARCH
6,
*CONTROLS, PARAMETERS=TIME INCREMENTATION
20, 30
*CONTROLS, FIELD=DISPLACEMENT, PARAMETERS=FIELD
0.05, 0.05,
```
## Define ***\*Output*** card for displacement, stress, and SDV.
```
*Output, field, frequency=10
*Node Output
NT, U
*Element Output
S, SDV1,SDV2,SDV4,SDV21,SDV34,SDV47,SDV60,SDV73,SDV86,SDV99,
SDV102,SDV103,SDV104,SDV105,SDV106,SDV107,SDV108,SDV115,SDV117,SDV135,
SDV142,SDV149,SDV156,SDV157,SDV172
```
## Change ***\*Sfilm*** definition to \*T***emperature file*** input for all the steps
```
*Sfilm, OP=NEW
Outer_Surface, ...etc
```
to
```
*TEMPERATURE, FILE=thermal, BSTEP=1, ESTEP=1
```
## Modify the output including the ***monitor DOF***
```
*Monitor, DOF=1, node=A_Monitor_Node, frequency=1
```
## **Start the simulation using the following command**
```
abaqus job=cylinder_2d_s
```
---
# Agent Instructions
This documentation is published with GitBook. GitBook is the documentation platform designed so that both humans and AI agents can read, navigate, and reason over technical content effectively. Learn more at gitbook.com.
## Querying This Documentation
If you need additional information that is not directly available in this page, you can query the documentation dynamically by asking a question.
Perform an HTTP GET request on the current page URL with the `ask` query parameter, and the optional `goal` query parameter:
```
GET https://dante-solutions-inc.gitbook.io/dante-6.3-help-documentation/introduction/create-stress-model-input-file-by-editing-thermal-model-input-file.md?ask=&goal=
```
`ask` is the immediate question: it should be specific, self-contained, and written in natural language.
`goal` is optional and describes the broader end goal you are ultimately trying to accomplish on behalf of the user. GitBook uses it to tailor the answer towards what is most useful for that goal.
The response will contain a direct answer to the question and relevant excerpts and sources from the documentation.
Use this mechanism when the answer is not explicitly present in the current page, you need clarification or additional context, or you want to retrieve related documentation sections.